CNC core profiling tools

For discussions related to designing and making ski/snowboard-building equipment, such as presses, core profilers, edge benders, etc.

Moderators: Head Monkey, kelvin, bigKam, skidesmond, chrismp

Post Reply
Jon Quarrie
Posts: 23
Joined: Wed Feb 16, 2011 8:10 pm

CNC core profiling tools

Post by Jon Quarrie » Mon Sep 18, 2017 8:00 pm

I'm about to start core profiling on a CNC shopbot and just wondered what type of cutting tools people are using to generate the profile tapers. Thanks in advance for any info.

barnboy
Posts: 47
Joined: Wed Oct 20, 2010 4:19 pm
Location: Adirondacks (Westport, NY)

Post by barnboy » Tue Sep 19, 2017 7:04 am

3-axis machine? For core tapering, I use a 3/4" diameter "Bowl & Tray" bit.

https://www.toolstoday.com/p-4945-bowl- ... ords=45984

Jon Quarrie
Posts: 23
Joined: Wed Feb 16, 2011 8:10 pm

Post by Jon Quarrie » Tue Sep 19, 2017 7:57 pm

Yes, 3 axis machine. Thanks for the info

twizzstyle
Posts: 2203
Joined: Tue Mar 07, 2006 8:25 pm
Location: Kenmore, Wa USA

Post by twizzstyle » Wed Sep 20, 2017 2:02 pm


rnordell
Posts: 47
Joined: Wed Feb 24, 2010 11:16 am
Contact:

Post by rnordell » Wed Sep 20, 2017 7:17 pm

Amana RC-2250. Works great and has indexable/replaceable cutters.

https://www.amazon.com/Amana-Tool-Surfa ... FHPKZ8095Z

sammer
Posts: 910
Joined: Wed Dec 19, 2007 10:37 pm
Location: Fernie B.C.
Contact:

Post by sammer » Thu Sep 21, 2017 7:01 am

twizzstyle wrote:I use a 1.5" straight flute.

https://www.amazon.com/gp/product/B000P ... UTF8&psc=1
I used bits like twizz for quite some time on my router bridge and they worked great.
I have 4 sitting in the shop now waiting for me to mail them away for resharpening.
Once they get a bit dull they can make your core blow up really fast!

Just ordered one of these to try. Gotta run down to Eureka tomorrow and pick it up.

https://www.amanatool.com/rc-2241-inser ... r-bit.html

Will post a bit of a review after it's had a bit of use.
Was torn between it and the RC-2242 with the curved edge.
Was finally sold when I found the inserts for the 2241 were pretty standard 12x12x1.5mm carbides and available just about anywhere.

sam
You don't even have a legit signature, nothing to reveal who you are and what you do...

Best of luck to you. (uneva)

rnordell
Posts: 47
Joined: Wed Feb 24, 2010 11:16 am
Contact:

Post by rnordell » Thu Sep 21, 2017 7:13 pm

I'm interested in how you like the rc-2241. It's nice that is ~$50 less than the rc-2250. One thing I like about the 2250 is it still has cutters on the bottom surface that will cut all the way to the centerline of the tool. Because it cuts to the centerline you can plunge and don't always have to ramp your cuts down into the material.

barnboy
Posts: 47
Joined: Wed Oct 20, 2010 4:19 pm
Location: Adirondacks (Westport, NY)

Post by barnboy » Wed Oct 04, 2017 9:39 am

I'm scratching my head a bit as to how you're using spoil board cleaners for profiling? On a rail/router bridge I get it, as you're effectively mimicking a 5-axis (or 4-axis I guess) router, but on a 3-axis machine, I don't see how a big wide flat bit gets you anything but trouble?

gav wa
Posts: 368
Joined: Tue Feb 18, 2014 8:58 pm
Location: Perth

Post by gav wa » Thu Oct 05, 2017 5:10 am

On most cnc software you can select your machining plane with code like g17, g18, g19. You can then cutter size compensation the tool on the z axis so your profile is still correct. Or you can even get lazy and not even learn to write code and just about any cam software will do it all for you :D

A bigger tool actually produces a flatter finish when ramping with a 3 axis machine.
That said, i only use 20 and 25mm tools but that is because i get them super cheap.

barnboy
Posts: 47
Joined: Wed Oct 20, 2010 4:19 pm
Location: Adirondacks (Westport, NY)

Post by barnboy » Thu Oct 05, 2017 7:22 am

Dig it!

rnordell
Posts: 47
Joined: Wed Feb 24, 2010 11:16 am
Contact:

Post by rnordell » Thu Oct 05, 2017 9:32 am

The scallop height on a 3axis machine from a 1.25" spoil board cutter is pretty small when looking at what it is doing while cutting a ski core. I was curious so I drew it up in CAD to measure it. Assuming a 10mm thickness change over a length of 800mm (about half the length of a slalom ski, 12mm underfoot, 2mm at tip), a 0.75" stepover of the bit results in a scallop height (from bottom of curved surface cut by bit to the "ridge" between passes) of 0.0015625". If the stepover is decreased to 0.375" the scallop becomes 0.00035". Worst case stepover of 1.25" the scallop is still only about 0.007". If the ramp angle is steeper, say a 10mm change over 400mm, now a 0.75" stepover with the same 1.25" bit jumps all the way up to 0.003125".

gav wa
Posts: 368
Joined: Tue Feb 18, 2014 8:58 pm
Location: Perth

Post by gav wa » Fri Oct 06, 2017 8:18 am

Ummm, yeah bro.
I think you are over thinking it all. Just try to picture it in your head.
I've spent 20 years running big cnc milling centres and even with all the new cadcam programs around I've found the guys i have taught who can picture it in their head properly go on to be good cnc tradesman.
Learn to right programs from scratch without cam tools and you will rarely have problems.

rnordell
Posts: 47
Joined: Wed Feb 24, 2010 11:16 am
Contact:

Post by rnordell » Fri Oct 06, 2017 12:00 pm

No problem here visualizing it in my head. Just trying to put some numbers to scallop height so people can understand the variables that go into producing it, no matter if you use cutter compensation, handwrite your g-code, or generate it with a CAM program. Regardless, scallop size is a function of cutter diameter, cutter shape (flat endmill v. ball endmill), toolpath stepover (% overlap), and the angle of the surface being cut relative to the rotation axis of the cutting tool. If surface roughness from the scallop height is trying to be controlled the effects of a flat endmill can be minimized with proper tool selection and toolpath generation, or it is best minimized with a 5-axis machine so that the axis of the endmill is always normal to the surface being cut.

Post Reply